General programming

Channel-specific

Programming is done in the usual fashion in conformity with DIN66025. The M/H function is output at the channel-specific part of the HLI.

For all M/H functions to be used, the synchronisation entry must be under the parameters P-CHAN-00041 (m_synch[mnr]) and P-CHAN-00027 (h_synch[mnr]) in the channel parameter list. This does not apply to default M functions.

Programing Example

Channel-specific programming

N20 X75

N30 X50

N40 X25 M8

N50 X0 H1

Axis-specific (programming)

An extended CNC syntax is used to output an M or H function to an axis.

If the output is always to take place at a specific axis, one option is to dispense with extended syntax and assign the M/H function to this axis by default.

The chosen axis must be in the channel. This is done by assigning the output axis configuration in the channel parameter list accordingly or by programming axis exchange commands during execution in the CNC program [PROG].

Axis-specific (parameterisation)

Configuration for default output at the axis-specific part of the HLI when programming with DIN 66025 syntax.

m_default_outp_ax_name[7]         Z

Programing Example

Axis-specific programming

N20 X75

N30 X50

N40 X25 M7     Output of M7 to the Z axis

N50 X[M7]      Output of M7 to the X axis

Explicit (extended syntax)

Programming in axis-specific syntax [PROG] for output to the axis-specific part of the HLI. In the case of explicit programming, an assignment from the channel parameter list is ignored.

Programing Example

Programming axis-specific syntax

N20 X75

N30 X50

N40 X25 X[M7]        Output of MM7 to the X axis

N50 X0

Mixed programming

Output of M or H functions to several axes and the channel range in the same NC block.

Programing Example

Mixed programming

N10 X[M7] S[M7] M7   Simultaneous output of M7 to the

                     X axis, the main spindle S and the

                     channel range

N20 X[H1] S[H1] H1   Corresponding example for the H function