Programming example

This example describes milling of a contour pocket defined in the NC program.

This results in the following cycle call:

Programing Example

Mill contour pocket

T9 D9                         ( Tool data )

M6                            ( Tool change )

G00 G90 M03 S6000 F5000       ( Technology data )

G00 Z100                      ( Go to z start position )

G00 X0 Y0                     ( Go to start position )

; cycle call parameter:

#VAR

V.L.SurfacePosition = 0                      ( Z position of workpiece surface )

V.L.RetractionPlane = 100                    ( Z position of return plane )

V.L.SafetyClearance = 10                     ( relative value of safety clearance )

V.L.FeedRateXY = 2000                        ( machining feedrate in XY )

V.L.FeedRateZ = 1000                         ( plunging feedrate )

V.L.Direction = 2                            ( clockwise machining )

V.L.DepthOfPocket = 20                       ( depth of pocket )

V.L.MaxIncrementZ = V.L.DepthOfPocket / 2    ( maximum infeed in Z )

V.L.MaxIncrementXY = V.G.WZ_AKT.R            ( maximum infeed in XY )

V.L.MachiningMode = 1                        ( roughing )

#ENDVAR

; contour definition:

#CONTOUR BEGIN[ID = 1]

G1 G90 X60 Y0

G1 G91 Y40

G1 G91 X-20

G1 G90 X20 Y60

G1 X0 Y40

G161 G03 X0 Y0 I0 J20

G1 X60

#CONTOUR END

G0 ZV.L.RetractionPlane

; cycle call:

L CYCLE [NAME = SysMillContourPocket.ecy @P1 = V.L.SurfacePosition, \

@P2 = V.L.RetractionPlane, @P3 = V.L.SafetyClearance \

@P4 = V.L.DepthOfPocket @P5 = V.L.MachiningMode @P6 = V.L.Direction\

@P7 = V.L.MaxIncrementZ @P8 = V.L.FeedRateZ \

@P9 = V.L.MaxIncrementXY @P10 = V.L.FeedRateXY @P50= 1 ]

M30