Programming example

Programing Example

Mill circular pocket

This example describes the milling and deburring operations for a circular pocket.

#VAR

; input parameters: pocket

V.L.SurfacePositionZ = 0 (Z position of workpiece surface)

V.L.RetractionPlane = 50 (Z position of retraction plane)

V.L.SafetyClearance = 2 (relative value of safety clearance in Z)

V.L.Depth = 10 (depth of pocket)

V.L.MaxIncrementZ = 10 (maximum infeed in Z)

V.L.MaxIncrementXY = 2.5 (maximum infeed in XY)

V.L.FeedZ = 2000 (plunging feedrate)

V.L.MachiningMode = 1 (machining mode)

V.L.Diameter = 20 (diameter of pocket)

; input parameters: chamfer

V.L.ChamferDepth = 1 (depth of chamfer)

V.L.ChamferFeedZ = 3000 (machining feedrate in Z)

V.L.ChamferMachDepth = 2 (machining depth for chamfer)

#ENDVAR

G54

; polynomial contouring for smooth movements

#CONTOUR MODE [DEV, PATH_DEV = 0.01]

G261

; positioning to the starting point

G00 X50 Y50

; tool change

T8 D8 (endmill 5mm)

; technology data

G90 M03 S6000 F4000

; cycle call for milling

L CYCLE [NAME=SysMillCircularPocket.ecy \

@P1 = V.L.SurfacePositionZ \

@P2 = V.L.RetractionPlane \

@P3 = V.L.SafetyClearance \

@P4 = V.L.Depth \

@P5 = V.L.MaxIncrementZ \

@P6 = V.L.MaxIncrementXY \

@P21 = V.L.FeedZ \

@P31 = V.L.MachiningMode \

@P68 = V.L.Diameter \

]

; tool change

T9 D9 (chamfering mill)

; technology data

G90 M03 S6000 F2000

; cycle call for milling

L CYCLE [NAME=SysMillChamfer.ecy \

@P1 = V.L.SurfacePositionZ \

@P2 = V.L.RetractionPlane \

@P3 = V.L.SafetyClearance \

@P4 = V.L.ChamferMachDepth \

@P68 = V.L.Diameter \

@P100 = "SysMillCircularPocket" \

@P101 = V.L.ChamferDepth \

@P106 = V.L.ChamferFeedZ \

]

G260

M05

M30